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Create an assembly drawing with an exploded view and parts list.
Type:
Tutorial
Length:
5 min.
Tutorial resources
These downloadable resources will be used to complete this tutorial:
Transcript
00:03
In this tutorial, you create an assembly drawing with an exploded view and parts list.
00:09
With the Collar-Flange-Assembly.iam file open in Inventor, click New to create a new template.
00:16
Navigate to the Templates > Metric folder and select ANSI.dwg.
00:23
Click Create.
00:25
To change the sheet size, in the browser, right-click Sheet and select Edit Sheet.
00:31
In the Edit Sheet dialog, from the Size drop-down, select C.
00:36
Click OK.
00:38
Right-click the canvas, and from the Marking menu, select Base View.
00:43
Since the Collar Flange Assembly file is already open, the drawing view is pre-selected.
00:50
In the Drawing View dialog, set the Style to Hidden Line and the Scale to 2:1.
00:56
Place the Top view in the upper-left corner,
01:00
and then move your mouse down from the view and click to place a projected Front view.
01:06
Right-click and Click OK.
01:10
You can now create a Section view.
01:12
On the ribbon, Place Views tab, Create panel, click Section.
01:16
On the Top view, locate the center point, where the green dot is indicated.
01:21
Drag up to find the center of one of the holes with the indicated green dot,
01:26
and then drag out further with that line still lined up with the green dot, indicating the center of that hole feature.
01:34
Click to select a point for the end of the section line, and then from the Marking menu, click Continue.
01:39
Drag to the right and place the Section view.
01:43
You can place center lines on these views automatically.
01:47
Right-click the Section view, and from the Marking menu, select Automated Centerlines.
01:53
In the popup dialog, set the Projection to Objects in View, Axis Parallel, and then set Apply To to Cylindrical Features.
02:02
Click OK to place the center lines.
02:05
Repeat these steps to place center lines on the the Top and Front views.
02:19
On the Front view, you can place some overall dimensions.
02:23
Right-click the canvas, and from the Marking menu, select General Dimension.
02:28
Click the bottom, and then the top of the Front view,
02:32
and then drag to the left to place a dimension for the overall height of the entire assembly.
02:38
Click OK in the Edit Dimension Dialog.
02:42
You can add additional dimensions as needed for the drawing.
02:46
Next, you can place another new base view of an exploded view of this assembly.
02:51
Right-click the canvas, and from the Marking menu, select Base View.
02:56
in the Drawing View dialog, Component tab, click Open an existing file,
03:02
and then from the exercise file location, select the predefined Collar-Flange-Assembly.ipn presentation file.
03:11
Click Open.
03:13
Use the ViewCube to reorientate the drawing view to a 45-degree view,
03:19
and then drag the view into the position that you want.
03:23
In the Drawing View dialog, set the Style to Shaded with no hidden lines, and then click OK.
03:30
Now you can add a parts list to the canvas.
03:34
On the ribbon, Annotate tab, Table panel, click Parts List.
03:38
Select the first base view that you created, and then select OK.
03:44
Drag and release to place your parts list where you want in the drawing.
03:49
Now you can place item balloons.
03:52
On the ribbon, Annotate tab, Table panel, click Auto Balloon from the drop-down.
03:58
Select the exploded view, then drag to highlight all the items in that view.
04:04
In the Auto Balloon dialog, set the Placement to Horizontal, and click above the view to place the balloons in the drawing.
04:13
Click OK.
04:15
You can also realign these balloons.
04:18
Drag to select the balloons, right-click and select Align > To Edge.
04:25
Align the balloons to the angle of the edge line and then place the balloons where you want them.
Video transcript
00:03
In this tutorial, you create an assembly drawing with an exploded view and parts list.
00:09
With the Collar-Flange-Assembly.iam file open in Inventor, click New to create a new template.
00:16
Navigate to the Templates > Metric folder and select ANSI.dwg.
00:23
Click Create.
00:25
To change the sheet size, in the browser, right-click Sheet and select Edit Sheet.
00:31
In the Edit Sheet dialog, from the Size drop-down, select C.
00:36
Click OK.
00:38
Right-click the canvas, and from the Marking menu, select Base View.
00:43
Since the Collar Flange Assembly file is already open, the drawing view is pre-selected.
00:50
In the Drawing View dialog, set the Style to Hidden Line and the Scale to 2:1.
00:56
Place the Top view in the upper-left corner,
01:00
and then move your mouse down from the view and click to place a projected Front view.
01:06
Right-click and Click OK.
01:10
You can now create a Section view.
01:12
On the ribbon, Place Views tab, Create panel, click Section.
01:16
On the Top view, locate the center point, where the green dot is indicated.
01:21
Drag up to find the center of one of the holes with the indicated green dot,
01:26
and then drag out further with that line still lined up with the green dot, indicating the center of that hole feature.
01:34
Click to select a point for the end of the section line, and then from the Marking menu, click Continue.
01:39
Drag to the right and place the Section view.
01:43
You can place center lines on these views automatically.
01:47
Right-click the Section view, and from the Marking menu, select Automated Centerlines.
01:53
In the popup dialog, set the Projection to Objects in View, Axis Parallel, and then set Apply To to Cylindrical Features.
02:02
Click OK to place the center lines.
02:05
Repeat these steps to place center lines on the the Top and Front views.
02:19
On the Front view, you can place some overall dimensions.
02:23
Right-click the canvas, and from the Marking menu, select General Dimension.
02:28
Click the bottom, and then the top of the Front view,
02:32
and then drag to the left to place a dimension for the overall height of the entire assembly.
02:38
Click OK in the Edit Dimension Dialog.
02:42
You can add additional dimensions as needed for the drawing.
02:46
Next, you can place another new base view of an exploded view of this assembly.
02:51
Right-click the canvas, and from the Marking menu, select Base View.
02:56
in the Drawing View dialog, Component tab, click Open an existing file,
03:02
and then from the exercise file location, select the predefined Collar-Flange-Assembly.ipn presentation file.
03:11
Click Open.
03:13
Use the ViewCube to reorientate the drawing view to a 45-degree view,
03:19
and then drag the view into the position that you want.
03:23
In the Drawing View dialog, set the Style to Shaded with no hidden lines, and then click OK.
03:30
Now you can add a parts list to the canvas.
03:34
On the ribbon, Annotate tab, Table panel, click Parts List.
03:38
Select the first base view that you created, and then select OK.
03:44
Drag and release to place your parts list where you want in the drawing.
03:49
Now you can place item balloons.
03:52
On the ribbon, Annotate tab, Table panel, click Auto Balloon from the drop-down.
03:58
Select the exploded view, then drag to highlight all the items in that view.
04:04
In the Auto Balloon dialog, set the Placement to Horizontal, and click above the view to place the balloons in the drawing.
04:13
Click OK.
04:15
You can also realign these balloons.
04:18
Drag to select the balloons, right-click and select Align > To Edge.
04:25
Align the balloons to the angle of the edge line and then place the balloons where you want them.
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