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Generate a drawing from a 3D model, adjust the settings for a base view, apply a projected view, and navigate the tools and functions available in the Drawing workspace.
Type:
Tutorial
Length:
7 min.
Transcript
00:03
The Drawing workspace in Fusion enables you to generate professional 2D drawings from a 3D model.
00:10
Drawings can include detailed views, dimensions, annotations, tables,
00:16
and other elements that facilitate the documentation process and creation of manufacturing specifications.
00:23
To open the Drawing workspace, in the Workspace menu, select Drawing.
00:31
Then, select either From Animation or, in this case, From Design.
00:37
In the Create Drawing dialog, first, choose whether you want to create your drawings automatically or manually.
00:45
Then, identify the Contents of your drawing as the Full Assembly, visible objects only, or a manual selection of specific objects.
00:56
Next, in the Destination group, for the Drawing, select Create New.
01:03
In the Template drop-down, select whether you want to create your drawing From Scratch or browse for a specific template.
01:11
You can also set the Standard as ASME or ISO, specify the Units,
01:19
and select the Sheet Size, either from standard options, or by customizing your own.
01:25
Lastly, choose a Landscape or Portrait orientation, and then click OK to convert the model into a drawing.
01:34
When you generate a drawing, the system creates a 2D projection of the components you select.
01:40
The initial drawing view generated is referred to as the base view.
01:46
Click to place it anywhere on the sheet, or use the Drawing View dialog to adjust the appearance of the base view first.
01:54
For example, you can select a different Orientation; in this case, the Front view is used.
02:02
Then, adjust the visual Style to Visible Edges, Visible and Hidden Edges, Shaded, or Shaded with Hidden Edges.
02:12
The system automatically applies an appropriate scale for the base view;
02:16
however, you can adjust the Scale by selecting from the available options or by entering a custom value.
02:24
Here, select a 1:1 scale, and then click to place the base view on the sheet.
02:31
Back in the Drawing View dialog, you can adjust the Edge Visibility, including Tangent Edges, Interference Edges,
02:40
and Thread Edges, as well as apply Automated Center Marks and Center Lines.
02:47
Click OK to generate the 2D representation.
02:51
Now, take a moment to review the groups of tools on the Drawing workspace toolbar.
02:57
These include: a Create group, to generate additional views;
03:03
a Modify group, to move, rotate or delete objects;
03:09
and a Geometry group, to create center lines, center marks, center mark patterns, and extensions;
03:18
next is a Dimensions group, to create manual dimensions or use auto-dimensioning,
03:24
and to add specific types of dimensions, such as radius, diameter, and arc length;
03:31
followed by a Text group, to add notes, and to label or annotate important elements on a sheet;
03:39
the Symbols group is used to create surface texture symbols, datum identifiers, and weld symbols, among others;
03:48
and the Insert group is used to insert supplemental images;
03:53
next is the Tables group, to create tables, part lists, balloons for parts lists, and revision clouds;
04:02
and lastly, there is an Export group, to export your drawing to different formats, such as PDF, DWG, DXF, and CSV.
04:15
Once a base view is placed in the drawing, you can use it to generate a projected view.
04:21
A projected view is an additional orthographic view of the design that can be created in eight different orientations, relative to the parent view.
04:31
With the base view selected, on the toolbar, Create group, click Projected View.
04:39
Move your pointer to the desired location, and then click to place the projected view.
04:45
The orientation of the projected view is determined by the direction in which you move your pointer.
04:52
Once a view is created, you can add dimensions automatically, or in this case, add them manually.
04:59
Expand the Dimensions menu and select the Dimension tool, which identifies the correct type of dimension based on the selected object.
05:10
For example, select the circular opening, and the Dimension tool finds a radius, which you can click to place.
05:19
Select two edges for the distance between them, or select two points to place an align dimension.
05:27
Next, a second drawing with casters is opened to demonstrate table creation for an assembly.
05:34
Select Tables > Parts List, then drag the table to the desired location and click to place it in the drawing.
05:45
Once placed, the table populates with a parts list that includes an item number and quantity,
05:52
and corresponding balloons are applied to the drawing.
05:56
You can also customize the columns and formatting to make your list look different than the default options shown here.
06:04
Additionally, you can modify the Document Settings to control drawing visuals.
06:10
In the Browser, place your pointer over Document Settings and click Change Document Settings.
06:18
This opens the Document Settings dialog, which includes several tabs of settings that can be adjusted.
06:25
Once you have created your drawing, on the Application bar, click Save, add a Version Description, if needed, and then click OK.
06:37
This saves the design to your Fusion project folder, which is confirmed by clicking Show Data Panel.
06:45
You can also Export the design to PDF or DWG, for example, to print, share or view it with other drawing packages, like AutoCAD.
06:55
One of the key benefits of using the Drawing workspace is that any updates made to the 3D design can be easily applied to the drawing.
07:04
Additionally, with files saved in the cloud, you can collaborate on drawings for efficiency and for compliance with industry drawing standards.
Video transcript
00:03
The Drawing workspace in Fusion enables you to generate professional 2D drawings from a 3D model.
00:10
Drawings can include detailed views, dimensions, annotations, tables,
00:16
and other elements that facilitate the documentation process and creation of manufacturing specifications.
00:23
To open the Drawing workspace, in the Workspace menu, select Drawing.
00:31
Then, select either From Animation or, in this case, From Design.
00:37
In the Create Drawing dialog, first, choose whether you want to create your drawings automatically or manually.
00:45
Then, identify the Contents of your drawing as the Full Assembly, visible objects only, or a manual selection of specific objects.
00:56
Next, in the Destination group, for the Drawing, select Create New.
01:03
In the Template drop-down, select whether you want to create your drawing From Scratch or browse for a specific template.
01:11
You can also set the Standard as ASME or ISO, specify the Units,
01:19
and select the Sheet Size, either from standard options, or by customizing your own.
01:25
Lastly, choose a Landscape or Portrait orientation, and then click OK to convert the model into a drawing.
01:34
When you generate a drawing, the system creates a 2D projection of the components you select.
01:40
The initial drawing view generated is referred to as the base view.
01:46
Click to place it anywhere on the sheet, or use the Drawing View dialog to adjust the appearance of the base view first.
01:54
For example, you can select a different Orientation; in this case, the Front view is used.
02:02
Then, adjust the visual Style to Visible Edges, Visible and Hidden Edges, Shaded, or Shaded with Hidden Edges.
02:12
The system automatically applies an appropriate scale for the base view;
02:16
however, you can adjust the Scale by selecting from the available options or by entering a custom value.
02:24
Here, select a 1:1 scale, and then click to place the base view on the sheet.
02:31
Back in the Drawing View dialog, you can adjust the Edge Visibility, including Tangent Edges, Interference Edges,
02:40
and Thread Edges, as well as apply Automated Center Marks and Center Lines.
02:47
Click OK to generate the 2D representation.
02:51
Now, take a moment to review the groups of tools on the Drawing workspace toolbar.
02:57
These include: a Create group, to generate additional views;
03:03
a Modify group, to move, rotate or delete objects;
03:09
and a Geometry group, to create center lines, center marks, center mark patterns, and extensions;
03:18
next is a Dimensions group, to create manual dimensions or use auto-dimensioning,
03:24
and to add specific types of dimensions, such as radius, diameter, and arc length;
03:31
followed by a Text group, to add notes, and to label or annotate important elements on a sheet;
03:39
the Symbols group is used to create surface texture symbols, datum identifiers, and weld symbols, among others;
03:48
and the Insert group is used to insert supplemental images;
03:53
next is the Tables group, to create tables, part lists, balloons for parts lists, and revision clouds;
04:02
and lastly, there is an Export group, to export your drawing to different formats, such as PDF, DWG, DXF, and CSV.
04:15
Once a base view is placed in the drawing, you can use it to generate a projected view.
04:21
A projected view is an additional orthographic view of the design that can be created in eight different orientations, relative to the parent view.
04:31
With the base view selected, on the toolbar, Create group, click Projected View.
04:39
Move your pointer to the desired location, and then click to place the projected view.
04:45
The orientation of the projected view is determined by the direction in which you move your pointer.
04:52
Once a view is created, you can add dimensions automatically, or in this case, add them manually.
04:59
Expand the Dimensions menu and select the Dimension tool, which identifies the correct type of dimension based on the selected object.
05:10
For example, select the circular opening, and the Dimension tool finds a radius, which you can click to place.
05:19
Select two edges for the distance between them, or select two points to place an align dimension.
05:27
Next, a second drawing with casters is opened to demonstrate table creation for an assembly.
05:34
Select Tables > Parts List, then drag the table to the desired location and click to place it in the drawing.
05:45
Once placed, the table populates with a parts list that includes an item number and quantity,
05:52
and corresponding balloons are applied to the drawing.
05:56
You can also customize the columns and formatting to make your list look different than the default options shown here.
06:04
Additionally, you can modify the Document Settings to control drawing visuals.
06:10
In the Browser, place your pointer over Document Settings and click Change Document Settings.
06:18
This opens the Document Settings dialog, which includes several tabs of settings that can be adjusted.
06:25
Once you have created your drawing, on the Application bar, click Save, add a Version Description, if needed, and then click OK.
06:37
This saves the design to your Fusion project folder, which is confirmed by clicking Show Data Panel.
06:45
You can also Export the design to PDF or DWG, for example, to print, share or view it with other drawing packages, like AutoCAD.
06:55
One of the key benefits of using the Drawing workspace is that any updates made to the 3D design can be easily applied to the drawing.
07:04
Additionally, with files saved in the cloud, you can collaborate on drawings for efficiency and for compliance with industry drawing standards.
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