Work with Fusion drawing templates

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Within the Fusion Drawing workspace, drawing templates automate the creation of standardized drawings.

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Creating a template enables you to configure specific settings,

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such as formatting, annotations, and title blocks,

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that you want to remain consistent in all drawings.

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Using the template for new drawings saves time,

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and sharing it with team members can help to ensure compliance with any project, team, or company standards.

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To create a template, with your project open in the Design workspace, on the Application bar, click File > New Drawing Template.

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In the Create Drawing Template dialog, expand the Template drop-down to select whether you want to start from scratch,

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start with an existing template or drawing in the current project,

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or Browse to start with a drawing or template in another project.

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In this example, select From Scratch.

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Here, set the Standard to ASME, the Units to inches, and the Sheet Size to B, with a Landscape Orientation.

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Then, click OK to begin working in the Template contextual environment.

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Next, create a base view.

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On the toolbar, in the Create group, click Base View Placeholder.

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In the Placeholder View dialog, apply the desired settings.

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In this case, select Create New for the Instance, and for Representation, select Assembly.

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Set the Orientation to Front, select Visible and hidden edges for the Style,

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and leave the Scale at Automatic to automatically fit the view to the drawing size.

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Next, under Edge Visibility, leave Tangent Edges Off and select Interference Edges and Thread Edges.

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Then, for both Automatic Center Marks and Lines, select Holes.

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Now, move your pointer to the desired location, and then click to place the base view in the drawing.

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Click OK to close the dialog.

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Once the base view is placed, you can create projected views.

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In the Create group, click Projected View Placeholder.

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Select the base view, then move your pointer and click to place the projected view.

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The view that is created depends on the direction in which you drag your pointer.

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For example, if you drag a projected view directly under the base view, and then click to place it,

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you now have a projected view of the bottom of the assembly.

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For a view of the right side, drag and place a projected view to the right.

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You can also create an isometric view by dragging your pointer in a diagonal direction.

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Here, place the isometric view in the upper right corner, and then press Enter to end the Projected View command.

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To adjust the placement of a view, simply click and drag it to a new location.

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To modify a view style, in this case, the isometric view, right-click and select Edit View.

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Select the isometric view again, and then, in the Placeholder View dialog, change the Style to Hidden Line.

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You can also adjust other options, such as the Scale.

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Note that these changes can be made at any time and do not need to match the parent.

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When you are finished making changes, click Close.

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Next, on the toolbar, expand the Text menu and select Text to add a note.

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In the drawing, click to place the first corner,

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then drag the pointer and click again to specify the opposite corner.

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For demonstration purposes, notes are copied and pasted into the text box as shown.

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You can use the Text dialog to format the text.

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For example, select the note text and then click Numbering to format it as a numbered list.

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You can also update the Font, Height, Color, and other attributes.

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For example, select “Notes” in the text box, and then click Bold.

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Once you have finished formatting the text and adding any properties, click Close.

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After zooming in for a better view, simply click and drag the text box to adjust its placement as needed.

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Then, on the Navigation bar, click Fit to zoom back out.

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To add a table placeholder, expand the Tables menu and select Table Placeholder.

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Move your pointer to the desired location, and then click to place the table.

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Here, you can see the part listed and the bubble added to the isometric view.

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On the Application bar, click Save.

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Name the template, specify a Location, and then click Save again.

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Next, modify the Title Block.

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In the Browser, expand Sheet Settings, then right-click Title Block and select Edit Title Block.

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This opens the Title Block contextual environment,

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where you can edit the title block geometry, text, attributes, and images.

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To add an image, on the toolbar, click Insert > Image.

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From the Insert dialog, select the image, and then click Insert.

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Here, a company logo is added to the title block,

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and the placement is adjusted by using the X Distance, Y Distance, and Scale settings in the Image dialog.

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Click OK to place the image.

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To add an additional attribute, select Text > Attribute; or, select an attribute in the title block to view its settings.

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For example, select Size to open the Attribute dialog for Paper Size.

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Close the dialog by clicking in a blank space.

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Here, you see a number of attributes, including scale, weight, sheet number, and revision.

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To finish editing the title block, click Finish Title Block.

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To make further edits, you can also double-click the title block directly in the drawing template.

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When you are done, press Esc to end the command.

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To add a second sheet to your template, on the Sheet Bar, click Add.

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For this example, a new base view is created at the Component level and placed in the middle of the sheet,

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with Center Marks and Center Lines for Holes.

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The second sheet now contains a new base view.

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Save and Close the template.

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Now, you can use the template to create a new drawing.

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In the Design workspace, expand the Workspace menu and select Drawing > From Design.

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In the Create Drawing dialog, expand the Template drop-down and select the Standard Drawing Template you just created.

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Click OK, and the sheets are automatically generated,

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including the notes, the parts list, and the applicable sheets for each part.

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You can then make additional adjustments to the drawing as needed.

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For example, here, the base view is selected, and the Scale is adjusted to 1:1.

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You can also, for example, adjust the placement of the balloons,

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as well as add dimensions to the drawing.

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Save the drawing with a Name and Location, and then click Save again.

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Creating and sharing a new drawing template is a best practice

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for helping to ensure consistent and standardized drawings across your project or team.